SPICE Source Types and Parameters

Publish Date: May 16, 2008 | 6 Ratings | 4.17 out of 5 |  PDF

1. Overview

The National Instruments SPICE Simulation Fundamentals series is your free resource on the internet for learning about circuit simulation. The series is a set of tutorials and information on SPICE simulation, OrCAD pSPICE compatibility, SPICE modeling, and other concepts in circuit simulation.

For more information, see the SPICE Simulation Fundamentals main page.

The series is divided among a number of in-depth detailed articles that will give you HOWTO information on the important concepts and details of SPICE simulation.

Circuit simulation is an important part of any design process. By simulating your circuits, you can detect errors early in the process, and avoid costly and time consuming prototype reworking. You can also easily swap components to evaluate designs with varying bills of materials (BOMs).

 

SPICE Simulation Sources

SPICE allows users to specify input that varies in form. These inputs are used as voltage or current signals that drive circuitry during simulation. In Multisim, these sources are available in the Sources group of the master database.

The following sources are available in SPICE simulation.

 

 Pulse
 Sinusoidal
 Exponential
 Piece-Wise Linear
 Single Frequency FM
 
 

Back to Top

2. Using SPICE Simulation Sources

The table below gives detailed information on the usage of each SPICE source.

 Pulse

 

 Syntax  PULSE(V1 V2 TD TR TF PW PER)
 Example

VIN 3 0 PULSE(-1 1 2NS 2NS 2NS 50NS 100NS)

 

 Parameter  Description  Default Units
 V1  Initial value    Volts or Amps
 V2  Pulsed value    Volts or Amps
 TD  Delay time  0.0  Seconds
 TR  Rise time  Tstep  Seconds
 TF  Fall time  Tstep  Seconds
 PW  Pulse width  Tstop  Seconds
 PER  Period  Tstop  Seconds
       
       

 Sinusoid

 

 Syntax  SIN(VO VA FREQ TD THETA)
 Example

VIN 3 0 SIN(0 1 100MEG 1NS 1E10)IN 3 0 PULSE(-1 1 2NS 2NS 2NS 50NS 100NS)

 

 Parameter  Description  Default  Units
 V0  Offset    Volts or Amps
 VA  Amplitude    Volts or Amps
 FREQ  Frequency 1/Tstop  Hz
 TD  Delay  0.0  Seconds
 THETA  Damping Factor  0.0  1/Seconds
     
     

 Exponential

 

 Syntax  EXP(V1 V2 TD1 TAU1 TD2 TAU2)
 Example

VIN 3 0 EXP(-4 -1 2NS 30NS 60NS 40NS)

 

 Parameter  Description  Default  Units
 V1  Initial value    Volts or Amps
 V2  Pulsed value    Volts or Amps
 TD1  Rise delay time  0.0  Seconds
 TAU1  Rise time constant  Tstep  Seconds
 TD2  Fall delay time  TD1 + Tstep  Seconds
 TAU2  Fall time  Tstep  Seconds
       
     

 Piece-Wise Linear

 

 Syntax  PWL(T1 V1 <T2; V2 T3 V3 T4 V4 ...>)
 Example

VCLOCK 7 5 PWL(0 -7 10NS -7 11NS -3 17NS -3 18NS -7 50NS -7)

 

 Parameter  Description  Default  Units
 V1  Instantaneous voltage    Volts or Amps
 T1  Instantaneous time    Seconds
       
     

 Single Frequency FM

 

 Syntax  SFFM(VO VA FC MDI FS)
 Example

V1 12 0 SFFM(0 1M 20K 5 1K)IN 3 0

 

 Parameter  Description  Default  Units
 V0  Offset    Volts or Amps
 VA  Amplitude    Volts or Amps
 FC  Carier frequency  1/Tstop  Hz
 MDI  Modulation index    Seconds
 FS  Signal frequency  1/Tstop  Hz
       
     

 

Back to Top

Bookmark & Share

Ratings

Rate this document

Answered Your Question?
Yes No

Submit